,cnc machinist,cnc manufacturing,cnc mechanic,cnc mill,cnc milling center,cnc milling companies,cnc milling tools,cnc parts,cnc plasma cutter,cnc plasma cutting,cnc plasma table,cnc production,cnc router table,cnc screw machine,cnc service,cnc swiss,cnc turning,cnc turning center,cnc turning centers,cnc vertical lathe,horizontal cnc,how to cnc machine,machining cnc,manufacturing cnc machines,okuma cnc,plasma cnc machine,production cnc machining,troubleshooting cnc machines,used cnc machine tools,used cnc milling machines,vertical cnc lathe,what can a cnc machine make
I designed a table based on the geometry of a torus knot. I wanted to make the table from hardwood. This design was meant as a study of CNC cut wood joinery as well as achieving a high degree of curvature in a table made by 5-axis CNC milling.
Concept
A torus knot is a curve which lies on the surface of a torus (think donut shape). Here is an example:
I wrote a Python script inside Rhino to generate the geometry. It starts with a single curve like the one above. This post provides a Rhino Python script to generate torus knot curves.
Depending on the input curve a great many tables are possible. Here are some 3D printed models showing different forms. The table I choose to fabricate is the one in the middle.
You enter a variety of properties such as the number of pieces, the length of an edge cross section, and properties of the dovetail bit that'll be used to cut the joints.
Once you've answered the questions it generates all the required geometry for toolpath setup. Everything is layered separately for an easier time assigning toolpaths in the toolpath setup software - Mastercam. Each part is exported to a separate file if you like.
Here are all three versions of the table run through the script:
Data about the table is stored in the Rhino file as notes. Here you can see the max sizes, board feet required, and the size of the required block of wood for each piece.
Fabrication
The prototype table was made from a single piece of 16/4 Yellow Poplar. The board was 4" thick, 10" wide and 16' long.
Each piece is CNC machined in two phases. The first phase cuts the sides, top, back, front and make portion of the dovetail joint. Each surface is left with 1/8" of extra material. This allows the wood to move a bit after the internal stresses of cutting have occurred. The final 1/8" is removed in the second phase.
The first phase is cut on a pair of 6" high pods and held to the table using vacuum pressure. The wood is glued to an 3/4" thick MDF spoil board which can be cut into to accommodate the curvature of the part. Here are all the parts glued to the MDF. The MDF board is larger because the extra surface area was needed to get enough vacuum pressure to hold very securely.
Here's a part sitting on the pods. It's necessary to put them up on pods so the router head can reach the end to cut the dovetail and so it can swarf mill the top surface.
After the first phase is done the dovetail is fully milled. Each side except the bottom is milled to within 1/8" of the final surface.
Before the part can be milled in the next phase it has to be band sawn free from the MDF plate it was glued to. It's okay to leave up to 1/2" on the bottom of the piece - that'll be removed during the final milling.
The second phase of cutting involves holding the workpiece steady using an aluminum fixture. It holds the part using the dovetail joint. I designed and modeled the fixture in Rhino and made it from off-cut aluminum plates. I waterjet cut out the parts, then milled them on the CNC bed mill.
The assembled fixture allows the dovetail to be tightly clamped against the vertical plane of the fixture. A metal dowel pin is run through the fixture to ensure proper vertical alignment and prevent the part from sliding in the dovetail bracket during cutting.
The dovetail bracket which holds the dovetail end of the workpiece was cut with the same carbide tipped bit used to cut the dovetails. That, and correct setup, ensures a perfect fit.
The alignment of the fixture is critical. The milled front face of the base is carefully aligned with the grid in the table. Then the exact position of the fixture is measured using a dial gauge.
Those measured coordinates are entered as the "table origin" - so the CNC thinks that's the 0,0,0 point. This matches how they were exported in Rhino and imported into Mastercam.
Once held in the fixture the part can be milled on all five remaining faces. Here is a part prior to any cutting:
First the endgrain is cut back 1/8" and the dovetail socket is cut. Then the bottom is milled to the final profile. Then the sides and top are cut.
You can see that the final edges of the part are only 1/8" away from the aluminum fixture.
Any surface that turns yellow during the simulation is cut -including that screw.
Of all 30 parts only one could not be milled correctly. That's because the sweep from one part to the next is too great and would have resulted in a collision with the fixture as the top of the dovetail was cut. So the top of the dovetail (just a 3/4" wide strip) does not match the neighboring part in this single case.
That extra material had to be removed with a gouge and then sanded smooth.
Here are all 30 parts cut prior to assembly.
Video:
Assembly
The parts are glued up in pair. Then those pairs are glued up and so on...
Result
The table is sanded to remove any tool marks.
Walnut Version
Later I built another version of this table out of Walnut. It's discussed here.
